(ANSYS APDL STRUCTURAL) Beams

Preferences > structural > ok.

Pre - processor > element type > add/edit/delete > add > beams > 2 node 188 > ok > close.

Pre - processor > material properties> material model > structural > linear > elastic > isotropic > enter (EX = 1.2E5, PRXY = 0.34) > ok > materials > exit.

Pre - processor > section > beams > common section > enter [ID = 1, Name = beam I - section, Sub type (select I SECTION), w1=w2=w3=100, t1=t2=t3=10] > ok.

Pre - processor > modelling > create >nodes > in active cs > enter the below table.

Node No	X - location	Y - location	Z - location
1	0	0	0	Apply
101	4000	0	0	Apply
102	6000	0	0	Apply
103	10000	0	0	Apply
203	12000	0	0	Ok

NOTE: Lengths are in mm, but in the diagram, there are in Meters.

Pre - processor > modelling > create > nodes > fill between nodes > select 1 & 101 nodes > ok > number of nodes to fill = 99 > ok. (You will get the in between nodes of 2 to 100)

Pre - processor > modelling > create > nodes > fill between nodes > select 103 & 203 nodes > ok > number of nodes to fill = 99 > ok. (You will get the in between nodes of 104 to 202)

NOTE: We are using "fill between nodes" so that we can apply UDL.

Pre - processor > modelling > create > elements > auto number > thru nodes > select node 1 & 2 > ok.

Pre - processor > modelling > copy > elements > auto number > select element 1-2 > ok > number of copy (100) > ok.

Pre - processor > modelling > copy > elements > auto number > select element 103 - 104 > ok > number of copy (100) > ok.

Pre - processor > modelling > create > elements > auto number > thru nodes > select node 101 & 102 > ok.

Pre - processor > modelling > create > elements > auto number > thru nodes > select node 102 & 103 > ok.

Pre - processor > loads > define loads > apply > structural > displacement > on nodes > select node 1 > fix UX,UY,UZ,RX,RY > apply.

Pre - processor > loads > define loads > apply > structural > displacement > on nodes > select node 203 > fix UY > ok.

Pre - processor > loads > define loads > apply > structural > pressure > on beams > select "box" for selecting the nodes 1 to 101 at ones > select 1 to 101 in single selection > ok > load key - 2,  pressure value at node I = 2 > ok.

Pre - processor > loads > define loads > apply > structural > pressure > on beams > select "box" for selecting the nodes 103 to 203 at ones > select 103 to 203 in single selection > ok > load key - 2,  pressure value at node I = 3 > ok.

Pre - processor > loads > define loads > apply > structural > force/moment > on node > select 101 > ok > FY = -6000 (-6KN) > apply.

Pre - processor > loads > define loads > apply > structural > force/moment > on node > select 102 > ok > FY = -3000 (-3KN) > ok.

Solution > solve > current LS > ok > close.

General post processor > element table > define table > add > use label for item = bending, select "by sequence " in result data  item (left table), select SMISC in right table, and type "3" behind it > apply > use label for item = bendingg, select "by sequence " in result data  item (left table), select SMISC in right table, and type "16" behind it > apply > use label for item = shear, select "by sequence " in result data  item (left table), select SMISC in right table, and type "6" behind it > apply >  use label for item = shearr, select "by sequence " in result data  item (left table), select SMISC in right table, and type "19" behind it > ok > update > close.

General post processor  > plot results > contour plot  > line element table > set label item at I & J as bending & bengingg > ok.

General post processor > plot results > contour plot  > line element table > set label item at I & J as shear & shearr > ok.